Re: gEDA-user: gsch2pcb not finding pcb element

[Matt Tanner <matt.tanner@xxxxxxx>]

Thanks for the suggestions, Stuart.

I did a very thorough line-by-line analysis and finally discovered the 
problem. Yes, it was a "syntax" problem, but a tricky one (maybe a bug 
in gsch2pcb)

I found that this does not work:
 Element ( 0x00000000  "EZUSB"  ""  ""  0  0  0  0  0  100  0x00000000  )
but this does:
 Element( 0x00000000  "EZUSB"  ""  ""  0  0  0  0  0  100  0x00000000  )
The extra space character between "Element" and the first "(" made the 
difference. If there is a space then gsch2pcb won't find the component. 
If the space is NOT there - "Element(..." then gsch2pcb will find the 
component and put it into <project>.pcb.new, as expected.

Thanks again for the suggestions. I appreciate the help.

Matt

Stuart Brorson wrote:

> > Hello, 
> >
> > I have created a footprint for a particular component. I put it in the correct directory along with all my other components, but for some reason this one is not being seen by gsch2pcb. Any ideas? Thanks in advance for any help. 
> >
> > Here is what I get when I run "gsch2pcb -v". 
> > Note that gsch2pcb finds "/home/logometrix/geda_parts/pcb_elements//EZUSB", which is my new footprint. But then it does not recognize it and put it into <project>.pcb.new... 
> >    
>
> I have no solution, but some thoughts:
>
> *  I don't know what behavior PCB will evince if your EZUSB footprint
> has a syntax error, but it might just die silently like this.  Run
> PCB, and do "file -> load element data to buffer".  See if the
> footprint can be read in and placed.  Also, visually inspect the
> footprint for correctness using a text editor.
>
> *  I wonder if the double // in your path is causing your problem?  It
> shouldn't, but I am not certain gsch2pcb is rubust against stuff like
> this.
>
> *  For more verbose spew, you can say "gsch2pcb -v -v".  Maybe this
> will provide a clue.
>
> Stuart
>
>